Siemens SINUMERIK 828D Programming Manual page 95

Example 4: Repeat section between jump marker and ENDLABEL
Program code
N10 G1 F300 Z-10
N20 BEGIN1:
N30 X10
N40 Y10
N50 BEGIN2:
N60 X20
N70 Y30
N80 ENDLABEL: Z10
N90 X0 Y0 Z0
N100 Z-10
N110 BEGIN3: X20
N120 Y30
N130 REPEAT BEGIN3 P=3
N140 REPEAT BEGIN2 P=2
N150 M100
N160 REPEAT BEGIN1 P=2
N170 Z10
N180 X0 Y0
N190 M30
Example 5: Milling, machine drill position with different technologies
Program code
N10 CENTER DRILL()
N20 POS_1:
N30 X1 Y1
N40 X2
N50 Y2
N60 X3 Y3
N70 ENDLABEL:
N80 POS_2:
N90 X10 Y5
N100 X9 Y-5
N110 X3 Y3
N120 ENDLABEL:
N130 DRILL()
N140 THREAD(6)
N150 REPEAT POS_1
N160 DRILL()
N170 THREAD(8)
N180 REPEAT POS_2
N190 M30
Job planning
Programming Manual, 07/2010, 6FC5398-2BP40-0BA0
1.11 Repeat program section (REPEAT, REPEATB, ENDLABEL, P)
Comments
; Execute section from N110 to N120 three times.
; Execute section from N50 to N80 twice.
; Execute section from N20 to N80 twice.
Comments
; Load centering drill.
; Drilling positions 1
; Drilling positions 2
; Change drill and drilling cycle.
; Load tap M6 and threading cycle.
; Repeat program section once from POS_1 up to ENDLABEL.
; Change drill and drilling cycle.
; Load tap M8 and threading cycle.
; Repeat program section once from POS_2 up to ENDLABEL.
Flexible NC programming
95