Siemens sinumerik 840D sl Function Manual page 879

Examples
Example program for 3D face milling:
N10
N20 $TC_DP1[1,1] = 121
N30 $TC_DP3[1,1]=20
N40 $TC_DP6[1,1]=5
N60
N70
N50 $TC_DP7[1,1]=3
N80 X0 Y0 Z0 A0 B0 C0 G17 T1 D1 F12000
N90 TRAORI(1)
N100 B4=-1 C4=1
N110 G41 ORID CUT3DF G64 X10 Y0 Z0
N120 X30
N130 Y20 A4=1 C4=1
N140 B3=1 C3=5
N150 B3=1 C3=1
N160 X-10 A5=1 C5=2 ORIC
N170 A3=-2 C3=1
N180 A3=-1 C3=1
N190 Y-10 A4=-1 C4=3
N200 X-20 Y-20 Z10
N210 X-30 Y10 A4=1 C4=1
N220 A3=1 B3=0.5 C3=1.7
N230 X-20 Y30 A4=1 B4=-2 C4=3 ORID
N240 A3 = 0.5 B3=-0.5 C3=1
N250 X0 Y30 C4=1
N260 BSPLINE X20 Z15
N270 X30 Y25 Z18
N280 X40 Y20 Z13
N290 X45 Y0 PW=2 Z8
N300 Y-20
N310 G2 ORIMKS A30 B45 i-20 X25 Y-40 Z0
N320 G1 X0 A3=-0.123 B3=0.456 C3 =2.789
B4=-1 C4=5 B5=-1 C5=2
N330 X-20 G40
N340 M30
34
; Definition of tool D1
;Tool type (torus cutter)
; Length compensation
; Radius
; Smoothing radius
; Selection of the tool
; Plane definition
; Activate tool offset
; Outside corner, new plane definition
; Change in orientation with ORID
; Change in orientation with ORID
; Change in orientation with ORIC
; Change in orientation with ORIC
; New plane definition
; Inside corner with previous block
; Inside corner, new plane definition
; Change in orientation with ORIC
; Change in orientation
; Path movement, new plane,
; orientation
; with relative programming
; Spline onset, relative programming
; the orientation remains during
; spline active
; Helix, orientation with axis program
; Path movement, orientation, non-constant plane
; Deactivation of the tool offset
Special functions: 3D Tool Radius Compensation (W5)
Function Manual, 11/2006, 6FC5397-2BP10-2BA0