Example: Group Of Holes With Multiple Tools - HEIDENHAIN TNC 620 User Manual

8

Example: Group of holes with multiple tools

Program run:
Program the fixed cycles in the main program
Call the complete hole pattern (subprogram 1) in the
main program
Approach the groups of holes (subprogram 2) in
subprogram 1
Program the group of holes only once in
subprogram 2
0 BEGIN PGM UP2 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL CALL 1 Z S5000
4 L Z+250 R0 FMAX
5 CYCL DEF 200 DRILLING
Q200=2
Q201=-3
Q206=250
Q202=3
Q210=0
Q203=+0
Q204=10
Q211=0.25
Q395=0
6 CALL LBL 1
7 L Z+250 R0 FMAX
8 TOOL CALL 2 Z S4000
9 FN 0: Q201 = -25
10 FN 0: Q202 = +5
11 CALL LBL 1
12 L Z+250 R0 FMAX
13 TOOL CALL 3 Z S500
264
Subprograms and program section repeats | Programming examples
;SET-UP CLEARANCE
;DEPTH
;FEED RATE FOR PLNGNG.
;PLUNGING DEPTH
;DWELL TIME AT TOP
;SURFACE COORDINATE
;2ND SET-UP CLEARANCE
;DWELL TIME AT DEPTH
;DEPTH REFERENCE
Centering drill tool call
Retract the tool
Cycle definition: Centering
Call subprogram 1 for the entire hole pattern
Drill tool call
New depth for drilling
New plunging depth for drilling
Call subprogram 1 for the entire hole pattern
Reamer tool call
HEIDENHAIN | TNC 620 | Klartext Programming User's Manual | 01/2022