Siemens SINUMERIK 840D sl Programming Manual page 269

Programming example
Calibrate tool probe (machine-related)
Tool probe 1 is stationary but provides a switching signal. The calibration tool is inserted in
the turret as tool T7.
Values of the calibration tool T7 D1:
Tool type (DP1):
Cutting edge length (DP2):
Length 1 - geometry (DP3).
Length 2 - geometry (DP4):
Radius - geometry (DP6):
This radius must be taken into account in
selecting the starting position for calibration
of _TP[0,1], _TP [0,3] (increase distance
from probe by 2 × R).
Values of tool probe 1 in data block GUD6
which were determined manually to 5 mm
accuracy beforehand (relative to the
machine zero):
_TP[0.0] = 50, _TP[0.1] = 20
_TP[0.2] = 70, _TP[0.3] = 40
To obtain a minimum measurement path of 1 mm, the measurement path is programmed
with _FA = 1+5= 6 mm (max. total measurement path = 12 mm).
%_N_CALIBRATE_MTT_MPF
N05 G94 G90 DIAMOF
N10 T7 D1
N15 G0 SUPA Z300 X240
N20 _TZL=0.001 _PRNUM=1 _VMS=0 _NMSP=1
N21 _MVAR=0 _MA=2 _TSA=5 _FA=6
N30 CYCLE982
N35 G0 SUPA Z60
N38 _MA=1
N40 CYCLE982
N45 G0 SUPA X20
N48 _MA=2
N50 CYCLE982
N55 G0 SUPA Z0
N58 _MA=1
N60 CYCLE982
N65 G0 SUPA X240
N70 SUPA Z300
N99 M2
Measuring cycles
Programming Manual, 03/2009 Edition, 6FC5398-4BP10-2BA0
Measuring Cycles for Turning Machines
6.2 CYCLE982 Tool: Measure turning tools
500
3
L1 = 10
L2 = 40
R = 5
;Calibration tool
;Starting position in minus X direction,
;procedure when ZO is deactivated
;Parameters for calibration cycle
;Calibration in minus X direction
;Approach new starting position
;Select another measuring axis
;Calibration in minus Z direction
;Approach new starting position
;Calibration in plus X direction
;Approach new starting position
;Calibration in plus Z direction
;Approach change position in each axis
269