Contour Grooving - Cycle952 - Siemens SINUMERIK 840D sl Programming Manual

Programming cycles externally
18.1 Technology cycles
18.1.37

Contour grooving - CYCLE952

Programming
CYCLE952(STRING[100] _PRG, STRING[100] _CON, STRING[100] _CONR, INT
_VARI, REAL _F, REAL _FR, REAL _RP, REAL _D, REAL _DX, REAL _DZ,
REAL _UX, REAL _UZ, REAL _U, REAL _U1, INT _BL, REAL _XD, REAL _ZD,
REAL _XA, REAL _ZA, REAL _XB, REAL _ZB, REAL _XDA, REAL _XDB, INT
_N, REAL _DP, REAL _DI, REAL _SC, INT _DN, INT _GMODE, INT _DMODE,
INT _AMODE, INT _PK, REAL _DCH)
Parameters
No. Param Param
mask internal
1 PRG _PRG
2 CON _CON
3 CONR _CONR
4 _VARI
708
Explanation
Name of the stock removal program
Name of the program from which the updated contour of the blank is read (for residual
machining)
Name of the program into which the updated contour for the blank (see _AMODE TEN
THOUSANDS) will be written
Machining type
UNITS: Type of stock removal
1 = Longitudinal
2 = Transverse
3 = Parallel to contour
TENS: Machining process (see _GMODE HUNDREDS)
1 = Roughing
2 = Finishing
3 = Reserved
4 = Roughing, two-channel
5 = Finishing, two-channel
HUNDREDS: Machining direction
1 = Machining direction X -
2 = Machining direction X +
3 = Machining direction Z -
4 = Machining direction Z +
THOUSANDS: Infeed direction
1 = Externally X-
2 = Internally X +
3 = Front face Z -
4 = Rear face Z +
TEN THOUSANDS: Define effect of finishing allowances
0 = Separate UX and UZ finishing allowances
1 = Finishing allowance U parallel to contour
Programming Manual, 03/2013, 6FC5398-2BP40-3BA1
Job Planning