Rectangular Spigot Milling - Cycle76 - Siemens SINUMERIK 840D sl Programming Manual

18.1.17

Rectangular spigot milling - CYCLE76

Programming
CYCLE76(REAL _RTP, REAL _RFP, REAL _SDIS, REAL _DP, REAL _DPR, REAL
_LENG, REAL _WID, REAL _CRAD, REAL _PA, REAL _PO, REAL _STA, REAL
_MID, REAL _FAL, REAL _FALD, REAL _FFP1, REAL _FFD, INT _CDIR, INT
_VARI, REAL _AP1, REAL _AP2, REAL _FS, REAL _ZFS, INT _GMODE, INT
_DMODE, INT _AMODE)
Parameters
No. Param Param
mask internal
RP _RTP
1
Z0 _RFP
2
3 SC _SDIS
4 Z1 _DP
5 _DPR
6 L _LENG
W _WID
7
8 R _CRAD
9 X0 _PA
10 Y0 _PO
11 α0 _STA
12 DZ _MID
UXY _FAL
13
UZ _FALD
14
15 FX _FFP1
16 FZ _FFD
17 _CDIR
18 _VARI
19 L1 _AP1
20 W1 _AP2
FS _FS
21
ZFS _ZFS
22
Job Planning
Programming Manual, 03/2013, 6FC5398-2BP40-3BA1
Explanation
Retraction plane (abs)
Reference point of tool axis (abs)
Safety clearance (to be added to reference point, enter without sign)
Spigot depth (abs)
Spigot depth (inc) with respect to Z0 (enter without sign)
Spigot length, see _GMODE (enter without sign)
Spigot width, see _GMODE (enter without sign)
Spigot corner radius (enter without sign)
Reference point for spigot in 1st axis of plane (abs)
Reference point for spigot in 2nd axis of plane (abs)
Angle of rotation, angle between longitudinal axis (L) and 1st axis of plane
Maximum depth infeed (inc; enter without sign)
Finishing allowance, plane (inc), allowance at edge contour
Finishing allowance depth (inc), allowance at base (enter without sign)
Feedrate on contour
Depth infeed rate
Milling direction (enter without sign)
UNITS:
0 = Down-cut
1 = Up-cut
Machining
UNITS:
1 = Roughing
2 = Finishing
5 = Chamfer
Length of blank spigot
Width of blank spigot
Chamfer width (inc)
Insertion depth (tool tip) on chamfering (abs, inc), see _AMODE
Programming cycles externally
18.1 Technology cycles
667