Face Milling - Cycle61 - Siemens SINUMERIK 840D sl Programming Manual

18.1.14

Face milling - CYCLE61

Programming
CYCLE61(REAL _RTP, REAL _RFP, REAL _SDIS, REAL _DP, REAL _PA, REAL
_PO, REAL _LENG, REAL _WID, REAL _MID, REAL _MIDA, REAL _FALD, REAL
_FFP1, INT _VARI, INT _LIM, INT _DMODE, INT _AMODE)
Parameters
No. Param Param
mask internal
RP _RTP
1
Z0 _RFP
2
3 SC _SDIS
4 Z1 _DP
5 X0 _PA
6 Y0 _PO
X1 _LENG
7
Y1 _WID
8
9 DZ _MID
10 DXY _MIDA
11 UZ _FALD
12 F _FFP1
13 _VARI
_LIM
14
Job Planning
Programming Manual, 03/2013, 6FC5398-2BP40-3BA1
Explanation
Retraction plane (abs)
Reference point of tool axis, height of blank (abs)
Safety clearance (to be added to reference point, enter without sign)
Height of finished part (abs/inc), see _AMODE
Corner point 1 in 1st axis (abs)
Corner point 1 in 2nd axis (abs)
Corner point 2 in 1st axis (abs/inc,) see _AMODE
Corner point 2 in 2nd axis (abs/inc,) see _AMODE
Maximum depth infeed
Maximum plane infeed (for unit, see _AMODE)
Finishing allowance, depth
Machining feedrate
Machining type
UNITS: Machining
1 = Roughing
2 = Finishing
TENS: Machining direction
1 = Parallel to the 1st axis, in one direction
2 = Parallel to the 2nd axis, in one direction
3 = Parallel to the 1st axis, varying direction
4 = Parallel to the 2nd axis, varying direction
Limits
UNITS: Limit 1st axis negative
0 = No
1 = Yes
TENS: Limit 1st axis positive
0 = No
1 = Yes
HUNDREDS: Limit 2nd axis negative
0 = No
1 = Yes
Programming cycles externally
18.1 Technology cycles
661