Siemens SINUMERIK 840D sl Function Manual page 427

Program code
$TC_DP10[1,1]=0
$TC_DP11[1,1]=0
Program code
; Wear: Length and radius compensation
$TC_DP12[1,1] =0
Groove machining on the cylinder surface
Program code
N10 T1 D1 G54 G90 F5000 G94
N20 SPOS=0
N30 G0 X25 Z110
N40 TRACYL(40.)
N50 G19
N60 Y70
N70 G1 X15
N80 OFFN=10
N90 Z100 G42
N100 Z50
N110 Y10
N120 Y70
N130 Z100
N140 Z110 G40
N150 G0 X25 Y0
N170 TRAFOOF
N180 M30
Extended Functions
Function Manual, 10/2015, 6FC5397-1BP40-5BA3
7.2 TRACYL cylinder surface transformation (option)
Comment
; Angle for tapered milling tools
Comment
; Remaining parameters to $TC_DP24=0 (basis di-
mension/adapter)
Comment
; Tool selection, clamping compensation
; Switchover of the spindle to rotary axis opera-
tion, positioning at 0 degrees
; Approach the start position
; Activating TRACYL with the first TRACYL data set
and working diameter 40 mm
; Machining plane Y/Z (cylinder surface)
; Positioning over the groove center
; Infeed tool to groove base
; Define 10 mm groove side spacing relative to
groove center line
; TRC selection and approach to right groove wall
; G42: TRC right of the progr. contour (
center)
; Path I: Producing the groove section parallel
with the cylinder axis
; Path I: Producing the groove section parallel
with the circumference
; Path II: Producing the groove section parallel
with the circumference
; Path II: Producing the groove section parallel
with the cylinder axis
; Travel away from the groove wall and TRC dese-
lection
; Return to the initial position
; Deactivate transformation
; End of program
M1: Kinematic transformation
groove
427