HEIDENHAIN ITNC 530 - CYCLE PROGRAMMING User Manual page 426

U
Measuring log Q281: Definition of whether the TNC is
to create a measuring log:
0: No measuring log
1: Generate measuring log: with the standard setting
the TNC saves the log file TCHPR425.TXT in the
directory in which your measuring program is also
stored.
2: Interrupt the program run and display the
measuring log on the screen. Resume program run
with NC Start.
U PGM stop if tolerance error Q309: Definition of
whether in the event of a violation of tolerance limits
the TNC is to interrupt the program run and output an
error message:
0: Do not interrupt program run, no error message
1: Interrupt program run, output an error message
U Tool number for monitoring Q330: Definition of
whether the TNC is to monitor the tool (see "Tool
monitoring" on page 400): Input range: 0 to 32767.9,
alternatively tool name with max. 16 characters
0: Monitoring not active
>0: Tool number in the tool table TOOL.T
U
Setup clearance Q320 (incremental): Additional
distance between measuring point and ball tip. Q320
is added to MP6140. Input range 0 to 99999.9999,
alternatively PREDEF
U Traversing to clearance height Q301: Definition of
how the touch probe is to move between the
measuring points:
0: Move at measuring height between measuring
points
1: Move at clearance height between measuring
points
Alternatively PREDEF
426
Example: NC blocks
5 TCH PROBE 425 MEASURE INSIDE WIDTH
Q328=+75 ;STARTNG PNT 1ST AXIS
Q329=-12.5 ;STARTNG PNT 2ND AXIS
Q310=+0 ;OFFS. 2ND MEASUREMENT
Q272=1 ;MEASURING AXIS
Q261=-5 ;MEASURING HEIGHT
Q260=+10 ;CLEARANCE HEIGHT
Q311=25 ;NOMINAL LENGTH
Q288=25.05 ;MAX. LIMIT
Q289=25 ;MIN. LIMIT
Q281=1 ;MEASURING LOG
Q309=0 ;PGM STOP IF ERROR
Q330= ;TOOL
Q320=0 ;SETUP CLEARANCE
Q301=0 ;MOVE TO CLEARANCE
Touch Probe Cycles: Automatic Workpiece Inspection