Stock Removal Cycle - Cycle95 - Siemens SINUMERIK 840D Programming Manual

4
03.96
09.01
4.5 Stock removal cycle – CYCLE95
Programming
CYCLE95 (NPP, MID, FALZ, FALX, FAL, FF1, FF2, FF3, VARI, DT, DAM, _VRT)
Parameters
string
NPP
real
MID
real
FALZ
real
FALX
real
FAL
real
FF1
real
FF2
real
FF3
int
VARI
real
DT
real
DAM
real
_VRT
With SW
4.4 and
higher
© Siemens AG, 2002. All rights reserved
SINUMERIK 840D/840Di/810D Programming Guide Cycles (PGZ) – 11.02 Edition
4.5 Stock removal cycle – CYCLE95
Name of the contour subroutine
Infeed depth (enter without sign)
Final machining allowance in the longitudinal axis (enter without sign)
Final machining allowance in the facing axis (enter without sign)
Final machining allowance along contour (enter without sign)
Feedrate for roughing without relief cut
Feedrate for insertion into relief cut elements
Feedrate for finishing
Type of machining
Value range: 1 ... 12
HUNDREDS DIGIT (SW 6.2 and higher):
Values: 0...with rounding at the contour
No residual corners will remain, the contour is
rounded overlapping meaning that the contours are rounded
over several points of intersection.
2...without rounding at the contour
The machine always rounds to the previous roughing
intersection and then retracts. Depending on the ratio of
tool radius to infeed depth (MID), residual corners might
be left.
Dwell time for chip breaking during roughing
Path length after which each roughing cut is interrupted for chip
breaking
Retraction distance from contour for roughing, incremental
(enter without sign)
4
Turning Cycles
4-291