Feedrate F - Siemens SINUMERIK 808D ADVANCED Programming And Operating Manual

See the following illustration for linear interpolation with rapid traverse from point P1to P2:
Programming example
N10 G0 X100 Z65
Note
Another option for linear programming is available with the angle specification ANG=. (For more information, see Section
"Contour definition programming (Page 96)".)
Information
Another group of G functions exists for moving into the position (see Section "Exact stop/continuous-path control mode: G9,
G60, G64 (Page 82)"). For G60 exact stop, a window with various precision values can be selected with another G group.
For exact stop, an alternative instruction with non-modal effectiveness exists: G9.
You should consider these options for adaptation to your positioning tasks.
8.3.2

Feedrate F

Functionality
The feed F is the path velocity and represents the value of the geometric sum of the velocity components of all axes
involved. The axis velocities are determined from the share of the axis path in the overall path.
The feedrate F is effective for the interpolation types G1, G2, G3, CIP, and CT and is retained until a new F word is written.
For more information, see Sections "Linear interpolation with feedrate: G1 (Page 71)" and "Circular interpolation: G2, G3
(Page 71)".
Programming
F...
Remark: For integer values, the decimal point is not required, e.g.: F300
Unit of measure for F with G94, G95
The dimension unit for the F word is determined by G functions:
● G94 F as feedrate in mm/min
● G95 F as feedrate in mm/rev. (only relative to the spindle speed!)
Remark:
This unit of measure applies to metric dimensions. According to Section "Metric and inch dimensioning", settings with inch
dimensioning are also possible.
Programming example
N10 G94 F310
N20 G01 X60 Z60
N30 M5
N40 S200 M3
N50 G95 F0.8
N60 G01 X100 Z100
N70 M30
70
; Feedrate in mm/min
; Spindle rotation
; Feedrate in mm/revolution
Programming and Operating Manual (Turning)
6FC5398-5DP10-0BA2, 06/2015