Mill a slot at the programmed position (X0, Y0, Z0).
Mill slots at a programmed position pattern (e.g. full circle or grid).
The positions refer to the reference point:
Reference point X – (for single position only)
Reference point Y – (for single position only)
Reference point Z – (for single position only)
Angle of rotation of slot
Slot depth (abs) or depth relative to Z0 (abs) – (only for ∇, ∇∇∇, ∇∇∇ base and ∇∇∇
Maximum plane infeed
Maximum plane infeed as a percentage of the milling cutter diameter
- (only for ∇)
Maximum depth infeed - (only for ∇, ∇∇∇ rough finishing, ∇∇∇ and ∇∇∇ edge)
- (only for vortex milling)
Plane finishing allowance (slot edge) - (only for ∇, ∇∇∇ rough finishing and ∇∇∇ base)
Depth finishing allowance (slot base) - (only for ∇, ∇∇∇ rough finishing and ∇∇∇ edge )
Chamfer width for chamfering (inc) - (for chamfering only)
Insertion depth of tool tip (abs or inc) - (for chamfering only)
Long hole (LONGHOLE) - only for G code programs
Use the "Elongated hole" cycle to machine elongated holes arranged on a circle. The
longitudinal axis of the elongated hole is aligned radially.
In contrast to the groove, the width of the elongated hole is determined by the tool diameter.
Internally in the cycle, an optimum traversing path of the tool is determined, ruling out
unnecessary idle passes. If several depth infeeds are required to machine an elongated
hole, the infeed is carried out alternately at the end points. The path to be traversed in the
plane along the longitudinal axis of the elongated hole changes its direction after each
infeed. The cycle searches for the shortest path when changing to the next elongated hole.
The cycle requires a milling cutter with a "face tooth cutting over center" (DIN 844).
Operating Manual, 03/2010, 6FC5398-7CP20-1BA0
Programming technological functions (cycles)