Linear And Circular Movements In The Y Axis; Milling: Linear Movement G1 - HEIDENHAIN CNC PILOT 640 User Manual

6
6.6 Linear and circular movements in the Y
axis

Milling: Linear movement G1

G1 moves the tool on a linear path at the feed rate to the Final
point.
The execution of G1 varies depending on the working plane:
G17 Interpolation in the XY plane
Infeed in Z direction
Angle A—reference: positive X axis
G18 Interpolation in the XZ plane
Infeed in Y direction
Angle A—reference: negative Z axis
G19 Interpolation in the YZ plane
Infeed in X direction
Angle A—reference: positive Z axis
Parameters:
X: Diameter – target point
Y: Length – target point
Z: Length – target point
AN: Angle (reference: depends on the working plane)
Q: Intersect. pt. or Final point if the line segment intersects a
circular arc (default: 0)
0: Near point of intersection
1: Far point of intersection
BR: Chamf./round. – defines the transition to the next contour
element
When entering a Chamf./round., program the theoretical end
point.
No entry: Tangential transition
BR = 0: No tangential transition
BR > 0: Rounding radius
BR < 0: Width of chamfer
BE: Special feed rate factor for Chamf./round. (default: 1)
Special feed rate = active feed rate * BE (range: 0 < BE <= 1)
Programming:
X, Y and Z absolute, incremental, modal or ?
If more axes are available on your machine, additional
input parameters will be displayed, e.g. parameter B for
the B axis.
590
DIN/ISO Programming for the Y axis | Linear and circular movements in the Y axis
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017