4.28 Contour Follow-Up; Saving/Loading Contour Follow-Upg702; Contour Follow-Up On/Off G703 - HEIDENHAIN CNC PILOT 640 User Manual

4

4.28 Contour follow-up

Automatic Contour follow-up is not possible with program branches
or repetitions. In these cases you control the Contour follow-up with
the following commands.

Saving/loading Contour follow-upG702

G702 saves the current contour or loads a saved contour.
Parameters:
ID: Workpc. blank contour – name of the auxiliary workpiece
blank
Q: 0=save 1=load 2=internal
0: Saves the current contour. The contour follow-up is not
affected
1: Loads the specified contour. The contour follow-up is
continued with the loaded contour
2: The following cycle uses the internal workpiece blank
H: Memory number (range: 0 to 9)
V: 0=all, 1=variable, 2=blank – selection of information to be
saved
0: Everything (variable contents and workpiece blank contours)
1: Variable contents
2: Workpiece blank contours
G702 Q2 switches off the global Contour follow-up for the following
cycle. Once the cycle has been executed, the global Contour follow-
up is effective again.
The affected cycle uses the internal Workpiece blank. The cycle
determines the internal workpiece blank from the contour and the
tool position.
G702 Q2 must be programmed before the cycle.

Contour follow-up on/off G703

G703 is used to activate/deactivate the Contour follow-up.
Parameters:
Q: On=1 Off=0 – contour follow-up on/off
0: Off
1: On
438
DIN/ISO programming | Contour follow-up
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017