Additive Correction G149 - HEIDENHAIN CNC PILOT 640 User Manual

DIN/ISO programming | Tools, compensations

Additive correction G149

The control manages 16 tool-independent compensation values.
One G149 followed by a D number activates the additive
compensation function. G149 D900 deactivates the additive
compensation function. The compensation values are managed in
Program run submode.
User's Manual
Further information:
Parameters:
D: Corr. additiv (default: 900)
D = 900: Deactivates the additive compensation
D = 901-916: Activates the additive compensation D
Programming:
Program G149 one block before the block containing the path
of traverse to which the compensation is to apply, because the
compensation must be corrected before it becomes effective.
Additive compensation remains in effect up to:
the next G149 D900
the next tool change
End of program
The additive compensation is added to the tool
compensation.
Example: G149
. . .
N1 T3 G96 S200 G95 F0.4 M4
N2 G0 X62 Z2
N3 G89
N4 G42
N5 G0 X27 Z0
N6 G1 X30 Z-1.5
N7 G1 Z-25
N8 G149 D901
N9 G1 X40 BR-1
N10 G1 Z-50
N11 G149 D902
N12 G1 X50 BR-1
N13 G1 Z-75
N14 G149 D900
N15 G1 X60 B-1
N16 G1 Z-80
N17 G1 X62
N18 G80
. . .
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
Activate compensation
Deactivate compensation
4
313