Standardize C Axis G153; Short Path In C G154 - HEIDENHAIN CNC PILOT 640 User Manual

DIN/ISO programming | C-axis commands

Standardize C axis G153

G153 resets a traverse angle >360° or <0° to an angle between 0°
and 360°—without moving the C axis.
G153 is only used for lateral-surface machining. An
automatic modulo 360° function is carried out on the face.

Short path in C G154

G154 defines that the C axis moves on the shorter path during
positioning.
Parameters:
H: Traverse on shorter path On/Off
0: OFF
1: ON
Example: G154
. . .
N1 G110 C0
N2 G154 H1
N3 G110 C350
N4 G110 C10
N5 G154 H0
N6 G110 C350
. . .
HEIDENHAIN | User's Manual smart.Turn and DIN Programming | 12/2017
Traverse path -10°
Traverse path +20°
Traverse path +340°
4
393