Milling Circular Spigots - Cycle77 (Sw 5.3 And Later) - Siemens SINUMERIK 840D Programming Manual

03.96
04.00
3
3.14

Milling circular spigots - CYCLE77 (SW 5.3 and later)

Programming
CYCLE77 (_RTP, _RFP, _SDIS, _DP, _DPR, _PRAD, _PA, _PO, _MID, _FAL, _FALD, _FFP1,
_FFD, _CDIR, _VARI, _AP1)
Parameters
The following input parameters are always required:
_RTP
real
_RFP
real
_SDIS
real
_DP
real
_DPR
real
_PRAD
real
_PA
real
_PO
real
_MID
real
_FAL
real
_FALD
real
_FFP1
real
_FFD
real
_CDIR
int
_VARI
int
_AP1
real
 Siemens AG 2000 All rights reserved.
SINUMERIK 840D/840Di/810D/FM-NC Programming Guide, Cycles (PGZ) - 04.00 Edition
3.14 Milling circular spigots - CYCLE77 (SW 5.3 and later)
Retraction plane (absolute)
Reference plane (absolute)
Safety clearance (to be added to the reference plane, enter without sign)
Depth (absolute)
Depth relative to the reference plane (enter without sign)
Diameter of spigot (enter without sign)
Spigot center point, abscissa (absolute)
Spigot center point, ordinate (absolute)
Maximum depth infeed (incremental, enter without sign)
Final machining allowance on edge contour (incremental)
Final machining allowance at the base (incremental, enter without sign)
Feedrate on contour
Feedrate for depth infeed (or spatial infeed)
Milling direction: (enter without sign)
Value: 0...Climb milling
1...Opposed milling
2 with G2 (irrespective of spindle direction)
3...with G3
Type of machining
Value: 1...Roughing to final machining allowance
2...Finishing (allowance X/Y/Z=0)
Diameter of blank spigot
Milling Cycles
3
3-177