Milling Circular Pockets - Pocket4 - Siemens SINUMERIK 840D Programming Manual

Milling Cycles
3

3.10 Milling circular pockets - POCKET4

3.10 Milling circular pockets - POCKET4
The cycle POCKET4 is available with Software Version 4.
Programming
POCKET4 (_RTP, _RFP, _SDIS, _DP, _PRAD, _PA, _PO, _MID, _FAL, _FALD, _FFP1, _FFD,
_CDIR, _VARI, _MIDA, _AP1, _AD, _RAD1, _DP1)
Parameters
The following input parameters are always required:
_RTP
real
_RFP
real
_SDIS
real
_DP
real
_PRAD
real
_PA
real
_PO
real
_MID
real
_FAL
real
_FALD
real
_FFP1
real
_FFD
real
_CDIR
int
_VARI
int
3-150
Retraction plane (absolute)
Reference plane (absolute)
Safety clearance (to be added to the reference plane, enter without sign)
Pocket depth (absolute)
Pocket radius
Pocket center point, abscissa (absolute)
Pocket center point, ordinate (absolute)
Maximum infeed depth (enter without sign)
Final machining allowance on pocket edge (enter without sign)
Final allowance at base (enter without sign)
Feedrate for surface machining
Feedrate for depth infeed
Milling direction: (enter without sign)
Value: 0...Climb milling (as spindle rotation)
1...Opposed milling
2...With G2 (independent of spindle direction)
3...With G3
Type of machining: (enter without sign)
UNITS DIGIT:
Value: 1...Roughing
2...Finishing
TENS DIGIT:
Value: 0...Perpendicular to the pocket center with G0
1...Perpendicular to the pocket center with G1
2...Along a helix
SINUMERIK 840D/840Di/810D/FM-NC Programming Guide, Cycles (PGZ) - 04.00 Edition
03.96
08.97
3
 Siemens AG 2000 All rights reserved.