Slot2 - Circumferential Slot - Siemens SINUMERIK 840D sl Programming Manual

Note
The cycle is provided with new functions that are not on earlier software versions.
Consequently certain parameters in the screen form (<NUM>, <RAD>, <INDA>) are no
longer displayed. Multiple slots on one position pattern can be programmed using "MCALL"
and calling the desired position pattern, e.g. HOLES2.
3.25.1.8

SLOT2 - circumferential slot

Syntax
SLOT2(<RTP>, <RFP>, <SDIS>, <_DP>, <_DPR>, <NUM>, <AFSL>, <WID>,
<_CPA>, <_CPO>, <RAD>, <STA1>, <INDA>, <FFD>, <FFP1>, <_MID>,
<CDIR>, <_FAL>, <VARI>, <_MIDF>, <FFP2>, <SSF>, <_FFCP>, <_UMODE>,
<_FS>, <_ZFS>, <_GMODE>, <_DMODE>, <_AMODE>)
Parameters
No. Parameter Parameter
mask internal
1 RP
<RTP>
2 Z0
<RFP>
3 SC
<SDIS>
4 Z1
<_DP>
5
<_DPR>
6 N
<NUM>
7 α1
<AFSL>
8 W
<WID>
9 X0
<_CPA>
10 Y0
<_CPO>
11 R
<RAD>
12 α0
<STA1>
13 α2
<INDA>
14 FZ
<FFD>
15 F
<FFP1>
16 DZ
<_MID>
17
<CDIR>
18 UXY
<_FAL>
NC programming
Programming Manual, 12/2019, 6FC5398-2EP40-0BA0
Data type Meaning
REAL Retraction plane (abs)
REAL Reference point of tool axis (abs)
REAL Safety clearance (to be added to reference point, enter without sign)
REAL Slot depth (abs)
REAL Slot depth (inc) with respect to Z0 (enter without sign)
INT Number of slots
REAL Opening angle of the slot
REAL Slot width
REAL Reference point = Center point of circle, 1st axis of the plane
REAL Reference point = Center point of circle, 2nd axis of the plane
REAL Radius of the circle
REAL Starting angle
REAL Incrementing angle
REAL Depth infeed rate
REAL Feedrate
REAL Maximum depth infeed
INT Milling direction
REAL Finishing allowance on plane or slot edge
Work preparation
3.25 Programming cycles externally
0 = Down-cut
1 = Up-cut
1037