Deep Drilling Axial - HEIDENHAIN 548431-05 User Manual

Teach-in | Drilling cycles

Deep drilling axial

Select Drilling
Select Deep drilling axial
The cycle produces a hole on a front face in several passes.
Cycle parameters:
X, Z: Start point
C: Spindle angle – C-axis position
Z1: Start point drill (default: drilling starts from Z)
Z2: End point drill
P: 1st hole dpth (default: hole will be drilled in one pass)
IB: Hole depth reduct. val (default: 0)
JB: Minimum hole depth (default: 1/10 of P)
B: Return length (default: retract to Start point drill)
E: Period of dwell for chip breaking at end of hole (default: 0)
D: Retraction type – Retraction speed and infeed within the
hole (default: 0)
0: Rapid traverse
1: Feed rate
AB: Drilling lengths (default: 0)
V: Drilling variants (default: 0)
0: Without reduction
1: At end of the hole
2: At start of the hole
3: At start & end of hole
T: Tool number – turret pocket number
G14: Tool change point
Further information:
ID: ID no.
S: Cutting speed or Constant speed
F: Feed per revolution
CB: Brake off (1)
SCK: Safety clearance
Further information:
Page 180
G60: Deactivate Protection zone for the drilling operation
0: Active
1: Inactive
HEIDENHAIN | MANUALplus 620 | User's Manual | 12/2017
"Tool change point G14", Page 180
"Safety clearances SCI and SCK",
5
347