Recessing Radial Finishing - HEIDENHAIN 548431-05 User Manual

Teach-in | Recessing cycles

Recessing radial finishing

Select Recessing cycle
Select Recessing radial
Press the Finishing run soft key
The cycle machines the number of recesses defined in Number
of recess cycles Qn. The Start point and End point contour
parameters define the first recess (position, recess depth and
recess width).
Cycle parameters:
X, Z: Start point
X2, Z2: End point contour
Qn: Number of recess cycles (default: 1)
DX, DZ: Dist.to subsequent recess with respect to the
preceding recess
G47: Safety clearance
Further information:
T: Tool number – turret pocket number
G14: Tool change point
Further information:
ID: ID no.
S: Cutting speed or Constant speed
F: Feed per revolution
MT: M after T: M function that is executed after the tool call T
MFS: M at beginning: M function that is executed at the
beginning of the machining step
MFE: M at end: M function that is executed at the end of the
machining step
WP: No. of spindle – Displays which workpiece spindle is used
to execute the cycle (machine-dependent)
Main drive
Opposing spindle for rear-face machining
BW: Angle in the B axis (machine-dependent)
CW: Reverse the tool (machine-dependent)
HC: Shoe brake (machine-dependent)
DF: Miscellaneous function (machine-dependent)
Type of machining for technology database access:
Contour recessing
In this cycle you can specify how the floor element is
machined during the finishing process.
The control evaluates the recessFinishing (602414)
machining parameter for this purpose. If this parameter
is not defined, the floor element is divided in the center.
HEIDENHAIN | MANUALplus 620 | User's Manual | 12/2017
"Safety clearance G47", Page 180
"Tool change point G14", Page 180
5
263