HEIDENHAIN ITNC 530 User Manual page 245

Example: FK programming 1
0 BEGIN PGM FK1 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+10
4 TOOL CALL 1 Z S500
5 L Z+250 R0 FMAX
6 L X-20 Y+30 R0 FMAX
7 L Z-10 R0 F1000 M3
8 APPR CT X+2 Y+30 CCA90 R+5 RL F250
9 FC DR- R18 CLSD+ CCX+20 CCY+30
10 FLT
11 FCT DR- R15 CCX+50 CCY+75
12 FLT
13 FCT DR- R15 CCX+75 CCY+20
14 FLT
15 FCT DR- R18 CLSD- CCX+20 CCY+30
16 DEP CT CCA90 R+5 F1000
17 L X-30 Y+0 R0 FMAX
18 L Z+250 R0 FMAX M2
19 END PGM FK1 MM
HEIDENHAIN iTNC 530
Y
100
75
30
20
20
Define the workpiece blank
Define the tool
Tool call
Retract the tool
Pre-position the tool
Move to working depth
Approach the contour on a circular arc with tangential connection
FK contour section:
Program all known data for each contour element
Depart the contour on a circular arc with tangential connection
Retract in the tool axis, end program
X
50 75 100
245