Circle Of Holes - Holes2 - Siemens SINUMERIK 808D User Manual

R14=30
R15=20
R16=0
R17=10
R18=10
R19=5
R20=5
R21=0
R22=10
N10 G90 F300 S500 M3 T10 D1
N20 G17 G0 X=R14 Y=R15 Z105
N30 MCALL CYCLE82(R11, R10, R12, R13,
0, 1)
N40 LABEL1:
N41 HOLES1(R14, R15, R16, R17, R18,
R19)
N50 R15=R15+R22
N60 R21=R21+1
N70 IF R21<R20 GOTOB LABEL1
N80 MCALL
N90 G90 G0 X30 Y20 Z105
N100 M02
12.5.3

Circle of holes - HOLES2

Programming
HOLES2 (CPA, CPO, RAD, STA1, INDA, NUM)
Pa rameters
Pa rameter D a ta type
CPA REAL
CPO REAL
RAD REAL
STA1 REAL
INDA REAL
NUM INT
Fu n ction
Use this cycle to machine a circle of holes. The machining plane must be defined before the cycle is called.
The type of hole is determined through the drilling cycle that has already been called modally.
182
; Reference point for the row of holes in the first axis of
the plane
; Reference point for the row of holes in the second axis of
the plane
; Starting angle
; Distance from first hole to reference point
; Distance between the holes
; Number of holes per row
; Number of rows
; Row counter
; Distance between the rows
; Specification of the technological values
; Approach starting position
; Modal call of drilling cycle
; Call of row of holes cycle
; Calculate y value for the next line
; Increment line counter
; Return to LABEL1 if the condition is fulfilled
; Deselect modal call
; Approach starting position
; End of program
D e scription
Center point of circle of holes (absolute), first axis of the plane
Center point of circle of holes (absolute), second axis of the plane
Radius of circle of holes (enter without sign)
Starting angle
Range of values: -180<STA1≤180 degrees
Incrementing angle
Number of holes
Programming and Operating Manual (Milling)
6FC5398-4DP10-0BA6, 09/2017