Siemens SINUMERIK 808D User Manual page 184

Programming example 1: Circle of holes
The program uses CYCLE82 to produce four holes having a depth of 30 mm. The final drilling depth is specified as a relative
value to the reference plane. The circle is defined by the center point X70 Y60 and the radius 42 mm in the XY plane. The
starting angle is 33 degrees. The safety clearance in drilling axis Z is 2 mm.
N10 G90 F140 S170 M3 T10 D1
N20 G17 G0 X50 Y45 Z2
N30 MCALL CYCLE82(2, 0, 2, , 30, 0)
N40 HOLES2 (70, 60, 42, 33, 0, 4)
N50 MCALL
N60 M02
Programming example 1: Circle of holes
Proceed through the following steps:
1.
2.
3.
4.
184
Select the desired operating area.
Open the vertical softkey bar for available drilling cycles.
Press this softkey from the vertical softkey bar.
Press this softkey to open the window for this cycle. Parameterize the cycle as desired.
; Specification of technology values
; Approach starting position
; Modal call of the drilling cycle, with-
out dwell time, DP is not programmed
; Call of the circle-of-holes cycle; the
incremental angle is calculated in the
cycle since the parameter INDA has been
omitted
; Deselect modal call
; End of program
Programming and Operating Manual (Milling)
6FC5398-4DP10-0BA6, 09/2017