Face Milling - Cycle61 - Siemens Sinumerik 840D sl Programming Manual

16.1.14

Face milling - CYCLE61

Programming
CYCLE61(REAL _RTP, REAL _RFP, REAL _SDIS, REAL _DP, REAL _PA, REAL
_PO, REAL _LENG, REAL _WID, REAL _MID, REAL _MIDA, REAL _FALD, REAL
_FFP1, INT _VARI, INT _LIM, INT _DMODE, INT _AMODE)
Parameters
Param Param
No.
Mask intern
1
RP _RTP
2
Z0 _RFP
3
SC _SDIS
4
Z1 _DP
5
X0 _PA
6
Y0 _PO
7
X1 _LENG
8
Y1 _WID
9
DZ _MID
10
DXY _MIDA
11
UZ _FALD
12
F _FFP1
13
_VARI
Job planning
Programming Manual, 02/2011, 6FC5398-2BP40-1BA0
Explanation
Retraction plane (abs)
Reference point of tool axis, height of blank (abs)
Safety clearance (to be added to reference point, enter without sign)
Height of finished part (abs/inc), see _AMODE
Corner point 1 in 1st axis (abs)
Corner point 1 in 2nd axis (abs)
Corner point 2 in 1st axis (abs/inc,) see _AMODE
Corner point 2 in 2nd axis (abs/inc,) see _AMODE
Maximum depth infeed
Maximum plane infeed (for unit, see _AMODE)
Finishing allowance, depth
Machining feedrate
Machining type
UNITS: Machining
1 = Roughing
2 = Finishing
TENS: Machining direction
1 = parallel to the 1st axis, in one direction
2 = parallel to the 2nd axis, in one direction
3 = parallel to the 1st axis, varying direction
4 = parallel to the 2nd axis, varying direction
Programming cycles externally
16.1 Technology cycles
763