Activate 3D Tool Tool Offsets - Siemens sinumerik 840d Programming Manual

Tool Offsets
8
8.5 Activate 3D tool offsets
840D
NCU 572
NCU 573
8.5 Activate 3D tool offsets
Explanation
CUT3DC
CUT3DFS
CUT3DFF
CUT3DF
G40 X Y Z
ISD=Value
The commands are modal and are in the same
group as CUT2D and CUT2DF.
The command is not deselected until the next
movement in the current plane is performed. This
always applies to G40 and is independent of the
CUT command.
Function
Tool orientation change is taken into account in tool
radius compensationTool radius compensation, 3D
for cylindrical tools.
The same programming commands apply to 3D tool
radius compensation as to 2D tool radius
compensation. With G41/G42, the left/right-hand
compensation is specified in the direction of
movement. The approach method is always NORM.
8-278
840Di
Activation of 3D radius offset for circumferential milling
3D tool offset for face milling with constant orientation. The tool
orientation is determined by G17–G19 and is not influenced by Frames.
3D tool offset for face milling with constant orientation. The tool
orientation is the direction determined by G17–G19 and possibly turned
by a Frame.
3D tool offset for face milling with orientation change (only with active 5-
axes transformation).
To deactivate: linear block G0/G1 with geometry axes
Insertion depth
SINUMERIK 840D/840Di/810D/FM-NC Programming Guide Advanced (PGA) − 04.00 Edition
04.00
8
 Siemens AG 2000. All rights reserved