Peripheral Milling: 3-D Radius Compensation With Tcpm And Radius Compensation (Rl/Rr) - HEIDENHAIN TNC 620 User Manual

Three-dimensional tool compensation (software option 2) 11.6
Example: Block format with surface normals without tool
orientation
LN X+31.737 Y+21.954 Z+33.165 NX+0.2637581 NY+0.0078922
NZ–0.8764339 F1000 M128
Example: Block format with surface normals and tool orientation
LN X+31.737 Y+21.954 Z+33.165 NX+0.2637581 NY+0.0078922
NZ–0.8764339 TX+0.0078922 TY–0.8764339 TZ+0.2590319 F1000
M128
LN:
Straight line with 3-D compensation
X, Y, Z:
Compensated coordinates of the straight-line
end point
NX, NY, NZ:
Components of the surface-normal vector
TX, TY, TZ:
Components of the normalized vector for
workpiece orientation
F:
Feed rate
M:
Miscellaneous function
Peripheral Milling: 3-D radius compensation with
TCPM and radius compensation (RL/RR)
The TNC displaces the tool perpendicular to the direction of
movement and perpendicular to the tool direction by the sum of
the delta values DR (tool table and TOOL CALL). Determine the
compensation direction with radius compensation RL/RR (see
figure, traverse direction Y+). For the TNC to be able to reach the
set tool orientation, you need to activate the function M128, See
"Maintaining the position of the tool tip when positioning with tilted
axes (TCPM): M128 (software option 2)", page 381. The TNC then
positions the rotary axes automatically so that the tool can reach
the defined orientation with the active compensation.
This function is possible only on machines for which
you can define spatial angles for the tilting axis
configuration. Refer to your machine manual.
The TNC is not able to automatically position the
rotary axes on all machines.
Refer to your machine manual.
Note that the TNC makes a compensating
movement by the defined
radius R defined in the tool table has no effect on the
compensation.
Danger of collision!
On machines whose rotary axes only allow limited
traverse, sometimes automatic positioning can
require the table to be rotated by 180°. In this case,
make sure that the tool head does not collide with
the workpiece or the clamps.
TNC 620 | User's Manual
HEIDENHAIN Conversational Programming | 5/2013
delta values. The tool
11
395