Siemens SINUMERIK 840D sl Programming Manual page 317

RPL:
<Angle>
Examples
Example 1: Rotation in the G17 plane
Program code
N10 G17 G54
N20 TRANS X20 Y10
N30 L10
N40 TRANS X55 Y35
N50 AROT RPL=45
N60 L10
N70 TRANS X20 Y40
N80 AROT RPL=60
N90 L10
N100 G0 X100 Y100
N110 M30
NC programming
Programming Manual, 12/2019, 6FC5398-2EP40-0BA0
Rotation around the geometry axis perpendicular to the active plane (G17, G18,
G19) by the specified angle
Reference Programmable frame $P_PFRAME
frame:
Reference point: Zero point of the current workpiece coordinate system set
with G54 ... G57, G505 ... G599
Angle specification in degrees.
Value range: -360° ≤ angle ≤ 360°
Comment
; Working plane X/Y, workpiece zero
; Absolute offset
; Subprogram call
; Absolute offset
; Additive rotation around the Z axis perpendicular
to the G17 plane through 45°
; Subprogram call
; Absolute offset
(resets all previous offsets)
; Additive rotation around the Z axis perpendicular
; to the G17 plane through 60°
; Subprogram call
; Retraction
; End of program
2.12 Coordinate transformations (frames)
With this workpiece, the shapes
shown recur in a program. In addition
to the work offset, rotations have to
be performed, as the shapes are not
arranged paraxially.
Fundamentals
317