Programming Examples; Example: Polar Hole Patterns - HEIDENHAIN TNC 620 User Manual

6
6.4

Programming Examples

Example: Polar hole patterns

0 BEGIN PGM HOLEPAT MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-40
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL CALL 1 Z S3500
4 L Z+250 R0 FMAX M3
5 CYCL DEF 200 DRILLING
Q200=2
Q201=-15
Q206=250
Q202=4
Q211=0
Q203=+0
Q204=0
Q211=0.25
Q395=0
6 CYCL DEF 220 POLAR PATTERN
Q216=+30
Q217=+70
Q244=50
Q245=+0
Q246=+360
Q247=+0
Q241=10
Q200=2
Q203=+0
204
;SET-UP CLEARANCE
;DEPTH
;FEED RATE FOR PLNGNG
;PLUNGING DEPTH
;DWELL TIME AT TOP
;SURFACE COORDINATE
;2ND SET-UP CLEARANCE
;DWELL TIME AT DEPTH
;DEPTH REFERENCE
;CENTER IN 1ST AXIS
;CENTER IN 2ND AXIS
;PITCH CIRCLE DIAMETR
;STARTING ANGLE
;STOPPING ANGLE
;STEPPING ANGLE
;NR OF REPETITIONS
;SET-UP CLEARANCE
;SURFACE COORDINATE
Fixed Cycles: Pattern Definitions | Programming Examples
Definition of workpiece blank
Tool call
Retract the tool
Cycle definition: drilling
Define cycle for polar pattern 1, CYCL 200 is called
automatically; Q200, Q203 and Q204 are effective as
defined in Cycle 220.
HEIDENHAIN | TNC 620 | User's manual for cycle programming | 10/2017