Siemens SINUMERIK 808D ADVANCED Programming And Operating Manual page 156

N10 G90 F30 S500 M3 T10 D1
N20 G17 G90 X20 Z105 Y30
N30 MCALL CYCLE82(105, 102, 2, 22, 0, 1)
N40 HOLES1(20, 30, 0, 10, 20, 5)
N50 MCALL
...
N60 G90 G0 X30 Z110 Y105
N70 MCALL CYCLE84(105, 102, 2, 22, 0, , 3, , 4.2, ,300, )
N80 HOLES1(20, 30, 0, 10, 20, 5)
N90 MCALL
N100 M02
Programming example: Grid of holes
Use this program to machine a grid of holes consisting of five rows with five holes each, which are arranged in the XY plane,
with a spacing of 10 mm between them. The starting point of the grid is at X30 Y20.
The example uses R parameters as transfer parameters for the cycle.
R10=102
R11=105
R12=2
R13=75
R14=30
R15=20
R16=0
R17=10
R18=10
R19=5
R20=5
R21=0
R22=10
156
; Reference plane
; Retraction plane
; Safety clearance
; Drilling depth
; Reference point for the row of holes in the first axis of
the plane
; Reference point for the row of holes in the second axis of
the plane
; Starting angle
; Distance from first hole to reference point
; Distance between the holes
; Number of holes per row
; Number of rows
; Row counter
; Distance between the rows
; Specification of the technological
values for the machining step
; Approach start position
; Modal call of drilling cycle
; Call of row-of-holes cycle; the cycle
starts with the first hole; only the
drill positions are approached in this
cycle
; Deselect modal call
; Change tool
; Approach position next to 5th hole
; Modal call of the tapping cycle
; Call of row of holes cycle starting
with the fifth hole in the row
; Deselect modal call
; End of program
Programming and Operating Manual (Milling)
6FC5398-4DP10-0BA1, 01/2014