Table of Contents
Advertisement
14
DATUM FROM INSIDE OF CORNER (Cycle 415, DIN/ISO: G415) 14.9
Q331 New datum in reference axis? (absolute):
Coordinate in the reference axis at which the TNC
should set the corner. Default setting = 0. Input
range -99999.9999 to 99999.9999
Q332 New datum in minor axis? (absolute):
Coordinate in the minor axis at which the TNC
should set the corner. Default setting = 0. Input
range -99999.9999 to 99999.9999
Q303 Meas. value transfer (0,1)?: Specify whether
the determined reference point is to be saved in the
datum table or in the preset table:
–1: Do not use! Is entered by the TNC when old
programs are read in (see "Characteristics common
to all touch probe cycles for datum setting",
page 326)
0: Write the measured datum into the active datum
table. The reference system is the active workpiece
coordinate system
1: Write the measured datum into the preset table.
The reference system is the machine coordinate
system (REF system).
Q381 Probe in TS axis? (0/1): Specify whether the
TNC should also set the datum in the touch probe
axis:
0: Do not set the datum in the touch probe axis
1: Set the datum in the touch probe axis
Q382 Probe TS axis: Coord. 1st axis? (absolute):
Coordinate of the probe point in the reference axis
of the working plane at which point the datum is
to be set in the touch probe axis. Only effective if
Q381 = 1. Input range -99999.9999 to 99999.9999
Q383 Probe TS axis: Coord. 2nd axis? (absolute):
Coordinate of the probe point in the minor axis of
the working plane at which point the datum is to be
set in the touch probe axis. Only effective if Q381 =
1. Input range -99999.9999 to 99999.9999
Q384 Probe TS axis: Coord. 3rd axis? (absolute):
Coordinate of the probe point in the touch probe
axis, at which point the datum is to be set in the
touch probe axis. Only effective if Q381 = 1. Input
range -99999.9999 to 99999.9999
Q333 New datum in TS axis? (absolute): Coordinate
in the touch probe axis at which the TNC should
set the datum. Default setting = 0. Input range
-99999.9999 to 99999.9999
359
HEIDENHAIN | TNC 320 | User's manual for cycle programming | 9/2016
Advertisement
Table of Contents
