HEIDENHAIN ITNC 530 - 6-2010 DIN-ISO PROGRAMMING User Manual page 215

Example: Linear movement with polar coordinates
%LINEARPO G71 *
N10 G30 G17 X+0 Y+0 Z-20 *
N20 G31 G90 X+100 Y+100 Z+0 *
N40 T1 G17 S4000 *
N50 G00 G40 G90 Z+250 *
N60 I+50 J+50 *
N70 G10 R+60 H+180 *
N80 G01 Z-5 F1000 M3 *
N90 G11 G41 R+45 H+180 F250 *
N100 G26 R5 *
N110 H+120 *
N120 H+60 *
N130 H+0 *
N140 H-60 *
N150 H-120 *
N160 H+180 *
N170 G27 R5 F500 *
N180 G40 R+60 H+180 F1000 *
N190 G00 Z+250 M2 *
N99999999 %LINEARPO G71 *
HEIDENHAIN iTNC 530
Definition of workpiece blank
Tool call
Define the datum for polar coordinates
Retract the tool
Pre-position the tool
Move to working depth
Approach the contour at point 1
Approach the contour at point 1
Move to point 2
Move to point 3
Move to point 4
Move to point 5
Move to point 6
Move to point 1
Tangential exit
Retract tool in the working plane, cancel radius compensation
Retract in the spindle axis, end of program
215