Circular Spigot Milling - Cycle77 - Siemens Sinumerik 840D sl Programming Manual

Programming cycles externally
16.1 Technology cycles
16.1.18

Circular spigot milling - CYCLE77

Programming
CYCLE77(REAL _RTP, REAL _RFP, REAL _SDIS, REAL _DP, REAL _DPR, REAL
_CDIAM, REAL _PA, REAL _PO, REAL _MID, REAL _FAL, REAL _FALD, REAL
_FFP1, REAL _FFD, INT _CDIR, INT _VARI, REAL _AP1, REAL _FS, REAL
_ZFS, INT _GMODE, INT _DMODE, INT _AMODE)
Parameters
Param Param
No.
Mask intern
1
RP _RTP
2
Z0 _RFP
3
SC _SDIS
4
Z1 _DP
5
_DPR
6 ∅
_CDIAM
7
X0 _PA
8
Y0 _PO
9
DZ _MID
10
UXY _FAL
11
UZ _FALD
12
FX _FFP1
13
FZ _FFD
14
_CDIR
15
_VARI
16 ∅ 1
_AP1
17
FS _FS
18
ZFS _ZFS
772
Explanation
Retraction plane (abs)
Reference point of tool axis (abs)
Safety clearance (to be added to reference point, enter without sign)
Spigot depth (abs)
Spigot depth (inc) with respect to Z0 (enter without sign)
Spigot diameter (enter without sign)
Reference point for spigot in 1st axis of plane (abs)
Reference point for spigot in 2nd axis of plane (abs)
Maximum depth infeed (inc; enter without sign)
Finishing allowance, plane (inc), allowance at edge contour
Finishing allowance depth (inc), allowance at base (enter without sign)
Feedrate on contour
Depth infeed rate
Milling direction (enter without sign)
UNITS:
0 = Climbing
1 = Conventional
Machining
UNITS:
1 = Roughing to final machining allowance
2 = Finishing (allowance X/Y/Z=0)
5 = Chamfer
Diameter of blank spigot
Chamfer width (inc)
Insertion depth (tool tip) on chamfering (abs/inc) see _AMODE)
Programming Manual, 02/2011, 6FC5398-2BP40-1BA0
Job planning