Siemens sinumerik 808d Programming And Operating Manual page 152

Cycles
2.5 Turning cycles
WIDG and DIAG (groove width and groove depth)
The parameters groove width (WIDG) and groove depth (DIAG) are used to define the form
of the groove. In its calculation, the cycle always assumes the point programmed under SPD
and SPL.
If the groove width is larger than that of the active tool, the width is removed in several steps.
When doing so, the whole width is distributed by the cycle equally. The maximum infeed is
95% of the tool width after deduction of the cutting edge radii. This provides a cutting
overlap.
If the programmed groove width is smaller than the real tool width, the error message 61602
"Tool width defined incorrectly" and machining is aborted. The alarm will also appear if a
cutting edge width equal to zero is detected in the cycle.
G90G95G18 ; Absolute dimensioning in the Z/X plane , revolutional feedrate
T8 ; Tool call
M01 ; Optional stop
M3S1000 ; Spindle speed
M08 ; Coolant ON
G0X50Z10 ; Starting point before the beginning of the cycle
G1F0.1 ; Specification of technology values
CYCLE93 (30.00000, -24.00000, 7.00000, 5.00000, , , ,1.00000, 1.00000, , , 0.20000,
0.20000, 1.50000, 0.20000, 5, 1.00000) ; Cycle call
G0X50
Z100 ; Retraction safety position
M9 ; Coolant OFF
STA1 (angle)
Use the STA1 parameter to program the angle of the oblique line at which the groove is to
be machined. The angle can assume values between 0 and 180 degrees and always refers
to the longitudinal axis.
152
Turning Part 2: Programming (Siemens instructions)
Programming and Operating Manual, 05/2012, 6FC5398-5DP10-0BA0