Siemens SINUMERIK 840D Programming Manual page 333

4
03.96
04.00
4.10 Extended stock removal cycle – CYCLE950 (SW 5.3 and higher)
_VRT (liftoff) and _ANGB (lift angle)
The parameter _VRT can be used to program the
amount of liftoff during roughing in both axes.
If _VRT=0 (parameter not programmed), liftoff is 1 mm.
It is also possible to program the angle at which the axis
is retracted from the contour in parameter _ANGB. If
nothing is programmed, the angle is 45°.
_SDIS (safety distance)
Parameter _SDIS determines the amount of clearance
for obstructions. This clearance is active for retraction
from a relief cut and approach to the next relief cut, for
example.
If no value is programmed, the clearance is 1 mm.
_NP5, _NP6, _NP7 (contour programming blank)
If a blank is programmed as a contour, it can be
programmed as a program name using parameter
_NP5 or as a program section with parameters
_NP6 and _NP7.
Otherwise, programming is carried out as for
finished parts (see _NP1, _NP2, _NP3).
_NP8 (name of contour program for updated
blank contour)
Cycle CYCLE950 can detect residual material that
cannot be removed with the active tool.
To continue this machining with a different tool, it is
possible to generate an updated blank contour
automatically. This is stored as a program in the parts
program memory. You can specify the program name in
parameter _NP8 with or without path details
(see sample program 3).
An updated blank contour is always generated when a
travel program is generated.
© Siemens AG, 2002. All rights reserved
SINUMERIK 840D/840Di/810D Programming Guide Cycles (PGZ) – 11.02 Edition
4
Turning Cycles
4-333