3.11 Programming Examples; Example: Drilling Cycles - HEIDENHAIN TNC 640 User Manual

Fixed Cycles: Drilling | Programming Examples

3.11 Programming Examples

Example: Drilling cycles

0 BEGIN PGM C200 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL CALL 1 Z S4500
4 L Z+250 R0 FMAX
5 CYCL DEF 200 DRILLING
Q200=2 ;SET-UP CLEARANCE
Q201=-15 ;DEPTH
Q206=250 ;FEED RATE FOR PLNGNG
Q202=5 ;PLUNGING DEPTH
Q210=0 ;DWELL TIME AT TOP
Q203=-10 ;SURFACE COORDINATE
Q204=20 ;2ND SET-UP CLEARANCE
Q211=0.2 ;DWELL TIME AT DEPTH
Q395=0 ;DEPTH REFERENCE
6 L X+10 Y+10 R0 FMAX M3
7 CYCL CALL
8 L Y+90 R0 FMAX M99
9 L X+90 R0 FMAX M99
10 L Y+10 R0 FMAX M99
11 L Z+250 R0 FMAX M2
12 END PGM C200 MM
HEIDENHAIN | User's manual for cycle programming | 10/2017
Definition of workpiece blank
Tool call (tool radius 3)
Retract the tool
Cycle definition
Approach hole 1, spindle ON
Cycle call
Approach hole 2, call cycle
Approach hole 3, call cycle
Approach hole 4, call cycle
Retract the tool, end program
3
117