3.11 Programming Examples; Example: Drilling Cycles - HEIDENHAIN TNC 620 User Manual

3
Fixed Cycles: Drilling

3.11 Programming Examples

3.11 Programming Examples

Example: Drilling cycles

0 BEGIN PGM C200 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL CALL 1 Z S4500
4 L Z+250 R0 FMAX
5 CYCL DEF 200 DRILLING
Q200=2
Q201=-15
Q206=250
Q202=5
Q210=0
Q203=-10
Q204=20
Q211=0.2
Q395=0
6 L X+10 Y+10 R0 FMAX M3
7 CYCL CALL
8 L Y+90 R0 FMAX M99
9 L X+90 R0 FMAX M99
10 L Y+10 R0 FMAX M99
11 L Z+250 R0 FMAX M2
12 END PGM C200 MM
92
;SET-UP CLEARANCE
;DEPTH
;FEED RATE FOR PLNGNG
;PLUNGING DEPTH
;DWELL TIME AT TOP
;SURFACE COORDINATE
;2ND SET-UP CLEARANCE
;DWELL TIME AT BOTTOM
;DEPTH REFERENCE
Definition of workpiece blank
Tool call (tool radius 3)
Retract the tool
Cycle definition
Approach hole 1, spindle ON
Cycle call
Approach hole 2, call cycle
Approach hole 3, call cycle
Approach hole 4, call cycle
Retract the tool, end program
TNC 620 | User's Manual Cycle Programming | 3/2014