Stock Removal Cycle - Cycle95 - Siemens SINUMERIK 840D Programming Manual

03.96
4
05.98
4.5 Stock removal cycle – CYCLE95
Programming
CYCLE95 (NPP, MID, FALZ, FALX, FAL, FF1, FF2, FF3, VARI, DT, DAM, _VRT)
Parameters
NPP
string
MID
real
FALZ
real
FALX
real
FAL
real
FF1
real
FF2
real
FF3
real
VARI
int
DT
real
DAM
real
_VRT
real
With SW
4.4 and
higher
Function
With this stock removal cycle you can machine a
contour programmed in a subroutine from a blank with
paraxial stock removal. Relief cut elements can be
included in the contour. With this cycle, contours can be
machined in the longitudinal and facing directions,
inside and outside. The technology is freely selectable
(roughing, finishing, complete machining). During
roughing, paraxial cuts are generated from the
maximum programmed infeed depth and when a point
of intersection with the contour is reached, the residual
corners are immediately removed cutting parallel to the
contour. Roughing is performed to the programmed
final machining allowance.
Finishing is performed in the same direction as
roughing. The tool radius compensation is automatically
selected and deselected by the cycle.
 Siemens AG 2000 All rights reserved.
SINUMERIK 840D/840Di/810D/FM-NC Programming Guide, Cycles (PGZ) - 04.00 Edition
4.5 Stock removal cycle – CYCLE95
Name of the contour subroutine
Infeed depth (enter without sign)
Final machining allowance in the longitudinal axis (enter without sign)
Final machining allowance in the facing axis (enter without sign)
Final machining allowance along contour (enter without sign)
Feedrate for roughing without relief cut
Feedrate for insertion into relief cut elements
Feedrate for finishing
Type of machining
Value range: 1 ... 12
Dwell time for chip breaking during roughing
Path length after which each roughing cut is interrupted for chip
breaking
Retraction distance from contour for roughing, incremental
(enter without sign)
Turning Cycles
4
4-227